Why "Smooth" Is Not a Specification

Write "smooth finish" on a drawing and you have written nothing. The machinist's smooth is a fine milling pass. The medical engineer's smooth is a polished bore. The difference between them is a factor of thirty in roughness and a factor of ten in price.

Ra is the number that ends the argument. It converts a subjective adjective into a measurable quantity that a supplier can quote, an inspector can verify, and a receiving department can reject a part against.

What Ra Actually Measures

Ra is the arithmetic average roughness: run a stylus across the surface, record the height profile, and average the absolute deviation from the mean line. In the US it is quoted in microinches (µin); the metric world uses micrometers (µm). One micrometer equals about 39.4 microinches, and the conversion appears constantly on drawings that mix supplier bases.

Some reference points on common processes:

  • Flame or plasma cut edge: 500 to 1,000 µin (12.5 to 25 µm)
  • Rough turning or milling: 250 µin (6.3 µm)
  • Standard machined finish, as-quoted default: 125 µin (3.2 µm)
  • Fine machining: 63 µin (1.6 µm)
  • Very fine machining or reaming: 32 µin (0.8 µm)
  • Grinding: 16 to 32 µin (0.4 to 0.8 µm)
  • Fine grinding or honing: 8 µin (0.2 µm)
  • Lapping and polishing: 1 to 4 µin (0.025 to 0.1 µm)
  • Mirror polish: under 1 µin

Ra has a well-known blind spot: it averages, so it cannot distinguish a surface with many shallow scratches from one with a single deep gouge. Where that distinction matters, sealing surfaces above all, engineers add Rz, which reports average peak-to-valley height, or Rmax for the worst single excursion. A gasket does not care about the average; it cares about the one deep scratch that leaks.

How It Gets Measured

The standard instrument is a contact profilometer with a diamond stylus dragged across a defined evaluation length. Handheld units cost a few thousand dollars and are common on shop floors. Optical and confocal instruments measure without contact and suit soft or delicate surfaces.

Two practical points. First, comparison specimens, small plates with reference surfaces you touch with a fingernail, are still used for rough sorting and are perfectly adequate for a 125 µin call, but they are not inspection data. Second, the measurement direction matters. Machined surfaces have lay, a directional pattern from the tool path, and Ra measured across the lay reads much higher than Ra measured along it. If you do not state the direction and the supplier measures the favorable one, you have a dispute with no resolution. Say it on the drawing.

What Each Grade Costs

Take a machined aluminum part at a baseline of $100 with an as-machined 125 µin finish.

  • 125 µin: included. This is what you get whether you ask or not.
  • 63 µin: roughly 1.1 to 1.3 times. A finishing pass at lower feed. Cheap.
  • 32 µin: roughly 1.4 to 1.8 times. Slower passes, sharper tooling, more careful setup.
  • 16 µin: roughly 2 to 3 times. Usually requires grinding as a separate operation on a separate machine.
  • 8 µin: roughly 3 to 5 times. Honing or fine grinding, with inspection on every part.
  • Under 4 µin: 5 to 15 times. Lapping or hand polishing, an artisanal operation priced by the hour.

The step from 32 to 16 is where cost accelerates, because that is usually where a second machine and a second setup enter the process. Specifying 16 µin on a face that nobody touches is one of the more common ways drawings quietly inflate a quote, alongside the tolerance mistakes discussed in what drives the price of a machined part.

Where Low Ra Genuinely Matters

Dynamic seal surfaces. A shaft running through a lip seal or an O-ring needs 8 to 16 µin. Rougher and the seal abrades; much smoother and it can fail to retain a lubricant film. Static O-ring glands tolerate 32 to 63 µin. The full geometry is in O-ring selection and gland design.

Fatigue-critical parts. Every machining mark is a stress riser and a crack initiation site. A shaft under cyclic bending load can gain meaningful fatigue life from polishing alone, which is one of the practical levers described in material fatigue in product design.

Bearing seats and precision fits. Roughness peaks flatten during assembly, so a rough press fit loses interference and a rough bore loses preload. The arithmetic behind that loss is part of press fits and clearance fits.

Patient-contact and food-contact surfaces. Cleanability is a regulatory concern, and typical requirements sit at 32 µin or below for surfaces that must be sanitized. This runs alongside material selection under ISO 10993 biocompatibility testing.

Surfaces that get coated or plated. Anodizing and plating follow the substrate faithfully. Every tool mark shows through and often looks worse afterward, since the coating adds contrast rather than hiding anything.

Where it does not matter: internal ribs, hidden faces, clearance holes, mounting surfaces under a bolt head, and anything painted with a textured finish. Leave those at the shop default and put the money where function needs it.

Molded and Cast Parts Use a Different Language

A molded plastic part inherits the finish of the mold cavity, so the specification is a mold finish grade rather than an Ra value: the SPI grades from A-1 mirror to D-3 heavy blast, or the VDI and Mold-Tech texture systems. Specifying an Ra on a molded surface confuses molders and usually gets ignored. Use the grade system described in mold texture selection, and remember that texture depth drives the draft angle the part needs.

Writing It on the Drawing

The surface finish symbol is a check mark with the value above it, placed on the surface it applies to or on a leader pointing at it. Best practice on a real production drawing:

Put a general note giving the default for all surfaces, typically 125 µin, then call out the specific surfaces that need better with individual symbols. State the units, state the measurement direction relative to the lay, and add Rz or Rmax alongside Ra on any sealing surface. Where finish is critical, name the acceptance method: profilometer reading with a stated cutoff length, not visual comparison. All of it belongs inside the same drawing discipline as GD&T, and a drawing that gets tolerances right and finish wrong still produces argument at receiving inspection.

Get the Callouts Right Before the RFQ Goes Out

Projects House reviews drawings before they reach suppliers, strips out finish and tolerance callouts that add cost without adding function, and tightens the ones that actually control performance. Send your drawing set through our contact form.